Skip to the chart
drillbitsizechart

Tap Drill Calculator

Enter diameter, pitch and target thread percentage. Get the exact drill size and the nearest real bits in every system, each with the thread it would cut.

Try

0.25 in, 20 TPI at 75% thread

0.2013ideal hole, in#7closest drill75%you will get

DrillInchmmThread
No.#70.20105.1175%
mm5.1 mm0.20085.176%
Frac13/640.20315.1672%
No.#60.20405.1871%
mm5.2 mm0.20475.270%
Frac3/160.18754.7696%
Formula
% thread = 76.98 × (major − drill) ÷ pitch
Basic minor diameter
0.1959 in (100% thread)

How the calculator works

Enter the thread's major diameter and its pitch (as TPI for inch threads, millimetres for metric) and a target thread percentage. The calculator returns the exact drill diameter for that percentage, then lists the real drills nearby in every system with the percentage each one would actually give. Use it for threads that are not in the standard tables (special pitches, 8-UN series, odd sizes) or when you want something other than 75%.

FormulaWhat it gives
drill = D − pct × P ÷ 76.98Drill diameter for a target percentage
pct = 76.98 × (D − drill) ÷ PPercentage a given drill will produce
dminor = D − 1.082532 × PBasic minor diameter (internal thread)
dpitch = D − 0.649519 × PPitch diameter

D is the major diameter and P the pitch, in the same unit. 76.98 is the constant for a 60° thread: it converts the radial difference to a percentage of the basic thread height (0.6495 × P on the diameter).

One thread, eight drills

What happens to a 1/4-20 thread as the drill changes. The standard #7 is in the middle of the useful range.

DrillInchThread %
#90.196083%
#80.199079%
#70.201075%
13/640.203172%
#60.204071%
#50.205569%
#40.209063%
7/320.218848%
#9 (0.1960)83%#8 (0.1990)79%#7 (0.2010)75%13/64 (0.2031)72%#6 (0.2040)71%#5 (0.2055)69%#4 (0.2090)63%7/32 (0.2188)48%
Green is the useful 60–80% band. Orange is above 80%: little extra strength, much more tap torque.

Picking a percentage

Material or jobTargetWhy
Mild steel, brass, aluminum (through hole)70–75%The standard; strength close to maximum
Stainless, titanium, tool steel55–65%Cuts tap torque roughly in half
Blind holes deeper than 1.5 × D60–65%Chip packing is the limit, not thread strength
Cast iron, plastics75–80%Brittle or soft threads benefit from more engagement
Thin sheet (under 1.5 pitches thick)80%+Only one or two threads engage
Thread-forming (roll) tapsUse the maker’s drillFormed threads need a larger hole; the formula above is for cutting taps
Thread strength: going from 75% to 100% engagement adds only about 5% strength but roughly triples the torque to turn the tap, according to the classic machinists’ tables. A broken tap costs more than a slightly weaker thread.

Sources: Wikipedia, "Unified Thread Standard" (UNC / UNF series, number-screw diameters); Wikipedia, "ISO metric screw thread" (ISO 261 coarse and fine pitches, basic profile); Wikipedia, "List of drill and tap sizes" (inch and metric tap drills, clearance holes).

Calculator questions

How do you calculate tap drill size?
Drill = major diameter − (thread % × pitch ÷ 76.98). For 75% that is about D − 0.974 × P. For 1/4-20: 0.25 − 0.75 × 0.05 ÷ 0.7698 = 0.2013 in, so a #7 (0.201 in).
What is the best thread percentage?
75% for most tapped holes in steel and aluminum. Use 60–65% in stainless or deep blind holes to protect the tap.
Is the simple rule "diameter minus pitch" correct?
For metric threads it gives 77% thread, close to the 75% standard, so yes. For inch threads it is the same idea: D − 1/TPI.
Does this work for thread-forming taps?
No. Forming taps displace metal instead of cutting it and need a larger hole, often about D − 0.5 × P. Use the tap maker’s drill size.
What does 76.98 mean in the formula?
It is 100 ÷ (2 × 0.6495): it converts the drill-to-major gap into a percentage of the full 60° thread depth.